Spiral Point Taps vs. Spiral Flute Taps: Key Differences and Applications

Gold-coated and bright threading taps beside curled metal chips and a drilled aluminum plate

Spiral point taps push chips forward, ahead of the tap, which makes them the standard choice for through holes. Spiral flute taps pull chips back up and out of the hole, which makes them the standard choice for blind holes. That single difference in chip direction drives most tap selection decisions on the shop floor.

Choosing the wrong one is a common cause of broken taps, rough threads and scrapped parts. This guide explains how each tap works, where each performs best, and how material and coating choices affect tool life.

What are spiral point taps and how do they work?

Close-up of spiral point and spiral flute taps
The angled point grind drives chips forward, out the bottom of the hole.

Spiral point taps, also called gun taps, have straight flutes with an angled grind on the cutting face at the front of the tap. This angled "point" shears the chip and drives it forward, out the bottom of the hole.

Because chips never travel back through the cut threads, spiral point taps produce clean threads and rarely jam on chip packing. Their flutes are also shallower than those of hand taps or spiral flute taps, leaving a thicker core. That extra cross-section gives more torsional strength, so they generally tolerate higher tapping speeds.

What are spiral flute taps and how do they work?

Spiral flute tap threading a hole in a square aluminum tube
A right-hand helix lifts chips up and out of the hole as the tap advances.

Spiral flute taps have helical flutes, like a twist drill. For right-hand threads, a right-hand helix lifts chips upward and out of the hole as the tap advances.

Helix angle matters:

  • Low helix (about 15°): Stronger cutting edges for harder or tougher materials such as alloy and stainless steels.
  • High helix (about 40–45°): Faster chip evacuation for soft, stringy materials such as aluminum, copper and some plastics.

Spiral flute taps usually have a short bottoming or semi-bottoming chamfer (roughly 1.5–3 threads), so they can thread close to the bottom of a blind hole.

Why not use spiral flute taps everywhere?

Their deeper flutes leave a thinner core, which lowers torque capacity. In through holes, the upward-moving chips can also wrap around the tap and scratch finished threads on reversal.

What are the key differences between spiral point and spiral flute taps?

FeatureSpiral point tapSpiral flute tap
Flute formStraight, with angled point grindHelical (typically 15°–45°)
Chip directionForward, ahead of the tapBackward, out of the hole
Ideal hole typeThrough holesBlind holes
Typical chamferPlug (about 3–5 threads)Bottoming or semi-bottoming (about 1.5–3 threads)
Core strengthHigherLower
Speed capabilityGenerally higherModerate
Main riskChips packing at the bottom of blind holesChip wrapping in through holes; breakage under high torque

If the hole goes all the way through, start with a spiral point tap. If it stops inside the part, start with a spiral flute tap. Bauron's taps design guide explains chamfer lengths and flute forms in more detail.

Which tap materials and coatings give the best wear resistance?

Tap substrate decides toughness and heat resistance. Coating decides friction, chip flow and how long the cutting edge stays sharp.

Tap materialStrengthsTypical use
HSS (M2)Tough, low cost, forgivingGeneral-purpose steel, aluminum, maintenance work
HSS-E / cobalt (M35, M42)Better hot hardness and abrasion resistanceStainless steel, alloy steel, higher volumes
Powder-metallurgy HSSFine, uniform structure; resists chipping and wearCNC production, tougher alloys
Solid carbideVery high hardness and wear resistance; brittleCast iron, hardened steel, rigid CNC setups
Rows of gold and bronze coated spiral flute taps
A coating only a few microns thick changes friction, chip flow and edge life.

Most taps also have a thin surface coating. A good coating helps the tap cut more smoothly, stay sharp longer and stop metal from sticking to it. For steel and stainless steel, choose a hard coating that handles heat well. For aluminum, copper and plastics, choose a smooth, polished tap that does not let soft material build up on the cutting edges. Our guide to end mill coatings compares the same coating families on milling tools.

Very hard taps last longest on modern, steady CNC machines. On older machines or when tapping by hand, a tougher cobalt tap usually lasts longer because it is less likely to chip or snap.

Where are spiral point taps and spiral flute taps used in industry?

ApplicationHole typeRecommended tap
M8 × 1.25 holes through a 304 stainless steel bracketThroughSpiral point, cobalt HSS with TiCN
M6 blind holes in a 6061 aluminum hydraulic manifoldBlindHigh-helix spiral flute, bright or CrN
1/2-13 threads in steel mounting plates for structural fabricationThroughSpiral point, HSS with steam oxide
Blind holes in a 4140 steel gearbox housingBlindLow-helix spiral flute, TiAlN
Gray cast iron pump bodiesThrough or blindStraight flute or spiral point; cast iron makes powdery chips that do not need helical evacuation

How does spiral drilling affect tapping results?

Two Bauron drills, a large coated drill and a gold twist drill, on a navy background
A sharp, correctly sized drill gives the tap a straight, clean hole to work in.

Thread quality starts with the drilled hole. In a spiral drilling and tapping sequence, the twist drill sets the minor diameter, straightness and surface condition the tap works with. Use the correct tap drill (6.8 mm for M8 × 1.25, #7 for 1/4-20 UNC) and keep the drill sharp, because a work-hardened hole wall in stainless steel shortens tap life quickly.

For blind holes tapped with spiral point taps, drill deep enough to leave chip space below the last full thread.

Is a spiral point tap set worth buying?

A spiral point tap set covering common sizes (for example M3–M12, or #4–1/2" UNC) suits maintenance shops and fabricators that thread mostly through holes. Production lines usually buy individual taps matched to one material and machine. Suppliers such as Bauron can help when a job needs a non-standard geometry, chamfer or coating that catalog sets do not cover.

What are the most common tapping problems and how do you fix them?

ProblemLikely causeSolution
Tap breaks at the bottom of a blind holeSpiral point tap packing chips; drill depth too shallowSwitch to a spiral flute tap or drill deeper
Chips wrap around the tap in through holesSpiral flute tap pulling long chips upwardUse a spiral point tap
Oversize or torn threads in aluminumBuilt-up edge, poor lubricationUse a bright or CrN-coated high-helix tap and a suitable cutting fluid
Rapid wear in stainless steelHeat, work hardening, wrong substrateUse cobalt HSS with TiCN, reduce speed, and apply coolant at the cut
Bell-mouthed or tapered threadsMisalignment between spindle and holeUse rigid (synchronized) tapping or a floating tap holder
Chipped teeth on carbide tapsVibration or spindle runoutImprove rigidity or switch to PM-HSS

Most tap failures trace back to three causes: the wrong flute type for the hole, an incorrect drilled hole, or poor lubrication.

Which tap should you choose?

Bauron machine tap for 1/2-28 UNEF threads on a navy background
Bauron taps carry their thread size and class on the shank, here 1/2-28 UNEF 3B.

Choose by where the chips should go. Spiral point taps push chips ahead of the tap, so they suit through holes and run faster thanks to their stronger core. Spiral flute taps pull chips out of the hole, so they suit blind holes, with the helix angle matched to the workpiece material.

After that, match the tap material and coating to the workpiece and machine, and start with a correctly sized, cleanly drilled hole. Getting these three choices right prevents most broken taps and rejected threads. For unusual materials, thread forms or production volumes, a tooling specialist such as Bauron can recommend or make a tap built for the job: browse our threading taps, start a custom tool design or request a quote.

Team Bauron

Ready to discuss a tooling challenge?

Ask a Bauron engineer about your part needs, material details, and machining goals, or browse the tool catalog.

Ask an Engineer Browse the Tool Catalog
Custom CNC tool manufacturing and 5-axis precision grinding

Frequently Asked Questions

01

Can spiral point taps be used in blind holes?

Yes, but only if there is room for the chips. A spiral point tap pushes chips down ahead of it, so the hole must be drilled deeper than the thread length to give those chips somewhere to go. If the hole is too shallow, chips pack at the bottom, the tap jams and it can break. When you cannot drill deeper, a spiral flute tap is the safer choice because it lifts chips out instead.

02

Is a spiral point tap the same as a gun tap?

Yes. "Gun tap" is a common shop-floor name for a spiral point tap, and catalogs may use either term. Both describe the same tool: straight flutes with an angled front edge that shoots chips forward out of the hole. If a supplier lists both names separately, check the drawing or description to confirm the design.

03

Which tap is stronger, spiral point or spiral flute?

Spiral point taps are generally stronger. Their flutes are shallower, which leaves more solid metal in the center of the tap, so it can take more twisting force before it breaks. Spiral flute taps have deeper grooves to carry chips out, which makes them slightly weaker. This is why spiral flute taps need more care in tough materials and in small thread sizes.

04

What helix angle should I choose for a spiral flute tap?

Match the twist of the flutes to the material. For harder steels and stainless steel, choose a gentle twist (about 15°), because it keeps the cutting edges strong. For aluminum, copper and other soft materials that make long, stringy chips, choose a steeper twist (about 40–45°), because it pulls chips out faster and stops them clogging the hole. For general steel work, a middle option (about 35°) is a common all-round choice.

05

Do I need spiral flute taps for cast iron?

Usually not. Cast iron breaks into short, powder-like chips instead of long curls, so the chips do not need to be lifted out by a twisted flute. Straight flute or spiral point taps handle cast iron well and are often stronger and cheaper. Cast iron is also abrasive, so a harder, wear-resistant tap tends to last longer than a standard one.

06

What should a spiral point tap set include?

A practical spiral point tap set should cover the thread sizes you use most often, for example M3 to M12 or #4 to 1/2" in inch sizes. Choose one tap grade that suits your usual materials, such as cobalt taps if you often work with stainless steel. A good set also lists the matching drill size for each tap, and a sturdy case helps protect the cutting edges from damage in storage.

07

Can the same tap be used on a CNC machine and by hand?

Yes, but these taps are designed to work best on machines, where the feed is steady and the tap stays perfectly straight. When tapping by hand, use a tap guide or drill press to keep the tap square to the hole, turn it smoothly and use cutting oil. Unlike hand taps, spiral point taps do not need to be backed off every turn to break chips, because they push chips ahead automatically.

Sources

Standards and references

The standards and reference documents behind the guidance on this page. Links open the publisher's site in a new tab.

  1. ISO 5967:1981 — Taps and thread cutting — Nomenclature of the main types and terminology (opens in a new tab)ISO

    Reference nomenclature of the main tap types and tapping terminology, intended for both tap users and manufacturers.

  2. ASME B94.9-2008 (R2023) — Taps: Ground Thread with Cut Thread Appendix (Inch and Metric Sizes) (opens in a new tab)ASME

    Covers tap nomenclature, marking and dimension and tolerance tables for straight-flute, spiral-flute, spiral-point, pipe and thread-forming taps.

  3. ISO 4957:2018 — Tool steels (opens in a new tab)ISO

    Specifies requirements for wrought tool steel grades, including the high-speed steels (M2- and M42-type grades) used for HSS and HSS-Co tools.

  4. ASP® powder metallurgy high-speed steels (opens in a new tab)Erasteel

    Steelmaker's explanation of how powder metallurgy permits higher alloy and carbide content, giving PM high-speed steels higher hardness and wear resistance.

  5. PLATIT Coating Guide — PVD coating specifications (opens in a new tab)PLATIT AG

    Coating-system maker's datasheets for AlTiN, TiAlN, nACo, nACRo, ZrN and DLC: nanohardness, friction coefficient, thickness and maximum service temperature.

BauronFlora BulutMechanical Engineer at Bauron
All articles
Get a QuoteDesign Tool